TESTPOINT INFORMATION FILE

Overview

A common method of testing both bare and assembled boards is to use a "bed of nails" test unit. This device makes connections to a large number of the exposed pads on the underside of the board, and then, in conjunction with a netlist and other information, checks the connectivity between the test-points. If there are any missing components, short circuits or dry joints, these will likely be detected and the board can be pulled out of the production line for repair or rejection.

In order to set up the testing machine, information is required as to the location of component pads on the underside of the board and the electrical nets that they are on. Proteus provides a special output file containing this information.

Generating the File

Use the Generate Testpoint File command on the Output Menu. Proteus prompts for a filename, defaulting to the TPI extension, and writes the file immediately.

The co-ordinates in the file are measured from the Output Origin, so set that first with the Set Output Origin command on the Output Menu if you have not already done so for the Gerber and Excellon output.

File Format

An example file is shown below:

LABCENTER PROTEUS TESTPOINT INFORMATION FILE

==================--------==================

Testpoint positions for C:\Projects\MyDesign.pdsprj

Fields: ID, Type, X, Y, Net, Layer

Units:  X, Y  - thou

Notes:  This file lists pads which are designated as testpoints on the layout.

        The X, Y value is the centre of drill hole or pad origin relative to the Output Origin.

        Vias are only listed if they are exposed through the solder resist.

"Q1:B","THRU",6150,5400,"#00000","TOP/BOTTOM"

"Q1:C","THRU",6050,5400,"UNREG","TOP/BOTTOM"

"Q1:E","THRU",5950,5400,"VOUT","TOP/BOTTOM"

"D1:A","THRU",6200,5250,"VOUT","TOP/BOTTOM"

"D1:K","THRU",5900,5250,"#00004","TOP/BOTTOM"

"R1:1","SURF",6350,5250,"VOUT","BOTTOM"

"R1:2","SURF",6350,4850,"#00001","BOTTOM"

"R2:1","SURF",6450,5250,"#00001","BOTTOM"

"R2:2","SURF",6450,4850,"GND=POWER","BOTTOM"

"Q2:E","THRU",5650,4950,"GND=POWER","TOP/BOTTOM"

"Q2:C","THRU",5650,5050,"#00004","TOP/BOTTOM"

"Q2:B","THRU",5650,5150,"#00005","TOP/BOTTOM"

"R3:1","THRU",6000,4750,"DIGITAL","TOP/BOTTOM"

"R3:2","THRU",5600,4750,"#00005","TOP/BOTTOM"

"C1:1","SURF",6250,4750,"ANALOG","BOTTOM"

"C1:2","SURF",6150,4750,"GND=POWER","BOTTOM"

"C2:1","SURF",5600,5350,"#00003","BOTTOM"

"C2:2","SURF",5700,5350,"#00004","BOTTOM"

"VIA","THRU",4650,4550,"#00003","TOP/BOTTOM"

"VIA","THRU",4550,5700,"#00004","TOP/BOTTOM"

There are a number of points that must be appreciated about this file:

  • Pads are identified as <PARTREF>:<PINNO>, or as VIA where the testpoint is a via.
  • Pad types are either THRU where there is a drill hole, or SURF if not.
  • Only pads which are designated as testpoints on the layout are listed, and only where the copper is exposed. Pads which are entirely covered by the solder resist are not listed.
  • The (x,y) co-ordinates are given in the current units, thou or millimetres, as stated on the Units line of the header. They represent the connection point of the pads, which is the point that you track to on the layout in order to achieve electrical connectivity.
  • The origin for the co-ordinates is the Output Origin; this is the same origin as is used for the Gerber and Excellon outputs.
  • The final field names the side or sides of the board on which the pad has exposed copper: TOP, BOTTOM or TOP/BOTTOM.
  • An unnetted pad is listed with a net of <NONE>.

The same information can be placed directly into your documentation. The Project Notes module offers Testpoints and Net Testpoint Count data objects which report the testpoints and their net coverage as formatted tables.

See Also:

Testpoints

Testpoint Reporting and Output

Manufacturing Report